Defining a shell edge load

You can create a shell edge load to define a general, shear, normal, or transverse traction or a moment along a shell edge.

Related Topics
Creating and modifying prescribed conditions
Understanding symbols that represent prescribed conditions
Using analytical expression fields
Creating expression fields
In Other Guides
Distributed loads

  1. Display the shell edge load editor using one of the following methods:

  2. Click the arrow to the right of the Distribution field, and select the option of your choice from the list that appears:

    • Select Uniform to define a load that is uniform over the shell edge.

    • Select User-defined to define the magnitude of the load in user subroutine UTRACLOAD (for Abaqus/Standard). See the following sections for more information:

    • Select an analytical field to define a spatially varying load. Only analytical fields that are valid for this load type are displayed in the selection list. Alternatively, you can click to create a new analytical field. (See The Analytical Field toolset for more information.)

  3. Click the arrow to the right of the Traction field, and select the option of your choice from the list that appears:

    • Select Normal to define a normal shell edge traction.

    • Select Transverse to define a transverse shell edge traction.

    • Select Shear to define a shear shell edge traction.

    • Select Moment to define a shell edge moment.

    • Select General to define a general shell edge traction.

  4. If you selected the General traction type, specify the load direction.

    1. Click next to Vector to specify the coordinates of the direction vector.
    2. By default, the traction components are specified with respect to the global axes. To refer to a local coordinate system for the direction components of the traction:

      • Select CSYS: Picked and click to pick a previously defined local coordinate system.

      • Select CSYS: User-defined and enter the name of a user subroutine that defines a local coordinate system.

    3. If you selected CSYS: Picked, you can define an additional rotation about one of the axes. Click the arrow to the right of the Additional rotation about axis field, select the axis about which the other two axes will be rotated, and enter a value for the additional rotation angle.

  5. In the Magnitude text field, enter the shell edge load magnitude (units FL−1).

  6. If desired, click the arrow to the right of the Amplitude field, and select the amplitude of your choice from the list that appears. Alternatively, you can click to create a new amplitude. (See The Amplitude toolset for more information.)

  7. If desired, click the arrow to the right of the Traction is defined per unit field, and select deformed area to define the shell edge load with respect to the current (deformed) area or undeformed area to define the shell edge load with respect to the reference (original) area.

  8. If you selected the General traction type, you can toggle off Follow rotation to define a non-follower load (i.e., the load always acts in a fixed global direction rather than rotating with the shell edge in a geometrically nonlinear analysis).

  9. Click OK to save your data and to exit the editor.